I'm using KiCad 5.1.6 and am unable to route a track to the pads on this component. Starting from the component the track won't leave the pad circle. Starting from another component the track will just go around the pad, but not connect to it.
Added 1 week, 3 days ago.
I ran into this earlier today with an inductor. The fix was to open the Properties for each of the affected pads in the Footprint Editor, go to the Local Clearance and Settings tab, and change the Pad Connection from "None" to "From parent footprint". Then I saved it to a new footprint and updated the component to use that one instead.
Answered 1 week, 2 days ago.
Thanks for waiting for us and sorry for the delay. We have updated the library, we fixed the slotted holes method for this footprint so the pads can be normally connected right now.
Hope that helps!
I wanted to add that KiCad version 4 router had a bug that allowed you to route outside the board edges and we were using the EdgeCuts layer to draw the slot outlines as we did not supported native slotted holes in KiCad at that moment. This bug has been fixed in KiCad 5.1 so the router is constrained routing traces inside the board edge layer. This was causing the observed router behavior, however as KiCad updated this we had also updated our methods, so we are now supporting native slotted holes and, this library you downloaded from 2018 was following the old method for slotted holes but it's now updated!
Thanks for your time,